        ## 5.2.1 Heat Transfer Theory

The Energy Equation

ANSYS FLUENT solves the energy equation in the following form: (5.2-1)

where is the effective conductivity ( , where is the turbulent thermal conductivity, defined according to the turbulence model being used), and is the diffusion flux of species . The first three terms on the right-hand side of Equation  5.2-1 represent energy transfer due to conduction, species diffusion, and viscous dissipation, respectively. includes the heat of chemical reaction, and any other volumetric heat sources you have defined.

In Equation  5.2-1, (5.2-2)

where sensible enthalpy is defined for ideal gases as (5.2-3)

and for incompressible flows as (5.2-4)

In Equations  5.2-3 and 5.2-4, is the mass fraction of species and (5.2-5)

where is 298.15 K.

The Energy Equation for the Non-Premixed Combustion Model

When the non-adiabatic non-premixed combustion model is enabled, ANSYS FLUENT solves the total enthalpy form of the energy equation: (5.2-6)

Under the assumption that the Lewis number (Le) = 1, the conduction and species diffusion terms combine to give the first term on the right-hand side of the above equation while the contribution from viscous dissipation appears in the non-conservative form as the second term. The total enthalpy is defined as (5.2-7)

where is the mass fraction of species and (5.2-8) is the formation enthalpy of species at the reference temperature .

Inclusion of Pressure Work and Kinetic Energy Terms

Equation  5.2-1 includes pressure work and kinetic energy terms which are often negligible in incompressible flows. For this reason, the pressure-based solver by default does not include the pressure work or kinetic energy when you are solving incompressible flow. If you wish to include these terms, use the define/models/energy? text command. When asked to include pressure work in energy equation? and include kinetic energy in energy equation?, respond by entering yes in the console window.

Pressure work and kinetic energy are always accounted for when you are modeling compressible flow or using the density-based solver.

Inclusion of the Viscous Dissipation Terms

Equations  5.2-1 and 5.2-6 include viscous dissipation terms, which describe the thermal energy created by viscous shear in the flow.

When the pressure-based solver is used, ANSYS FLUENT's default form of the energy equation does not include them (because viscous heating is often negligible). Viscous heating will be important when the Brinkman number, Br, approaches or exceeds unity, where (5.2-9)

and represents the temperature difference in the system.

When your problem requires inclusion of the viscous dissipation terms and you are using the pressure-based solver, you should activate the terms using the Viscous Heating option in the Viscous Model dialog box. Compressible flows typically have . Note, however, that when the pressure-based solver is used, ANSYS FLUENT does not automatically activate the viscous dissipation if you have defined a compressible flow model.

When the density-based solver is used, the viscous dissipation terms are always included when the energy equation is solved.

Inclusion of the Species Diffusion Term

Equations  5.2-1 and 5.2-6 both include the effect of enthalpy transport due to species diffusion.

When the pressure-based solver is used, the term is included in Equation  5.2-1 by default. If you do not want to include it, you can disable the Diffusion Energy Source option in the Species Model dialog box.

When the non-adiabatic non-premixed combustion model is being used, this term does not explicitly appear in the energy equation, because it is included in the first term on the right-hand side of Equation  5.2-6.

When the density-based solver is used, this term is always included in the energy equation.

Energy Sources Due to Reaction

Sources of energy , , in Equation  5.2-1 include the source of energy due to chemical reaction: (5.2-10)

where is the enthalpy of formation of species and is the volumetric rate of creation of species .

In the energy equation used for non-adiabatic non-premixed combustion (Equation  5.2-6), the heat of formation is included in the definition of enthalpy (see Equation  5.2-7), so reaction sources of energy are not included in .

When one of the radiation models is being used, in Equation  5.2-1 or 5.2-6 also includes radiation source terms. See Section  5.3 for details.

Interphase Energy Sources

It should be noted that the energy sources, , also include heat transfer between the continuous and the discrete phase. This is discussed further in Section  15.12.1.

Energy Equation in Solid Regions

In solid regions, the energy transport equation used by ANSYS FLUENT has the following form: (5.2-11)

 where = density = sensible enthalpy,  = conductivity = temperature = volumetric heat source

The second term on the left-hand side of Equation  5.2-11 represents convective energy transfer due to rotational or translational motion of the solids. The velocity field is computed from the motion specified for the solid zone (see this section in the separate User's Guide). The terms on the right-hand side of Equation  5.2-11 are the heat flux due to conduction and volumetric heat sources within the solid, respectively.

Anisotropic Conductivity in Solids

When you use the pressure-based solver, ANSYS FLUENT allows you to specify anisotropic conductivity for solid materials. The conduction term for an anisotropic solid has the form (5.2-12)

where is the conductivity matrix. See this section in the separate User's Guide for details on specifying anisotropic conductivity for solid materials.

Diffusion at Inlets

The net transport of energy at inlets consists of both the convection and diffusion components. The convection component is fixed by the inlet temperature specified by you. The diffusion component, however, depends on the gradient of the computed temperature field. Thus the diffusion component (and therefore the net inlet transport) is not specified a priori.

In some cases, you may wish to specify the net inlet transport of energy rather than the inlet temperature. If you are using the pressure-based solver, you can do this by disabling inlet energy diffusion. By default, ANSYS FLUENT includes the diffusion flux of energy at inlets. To turn off inlet diffusion, use the define/models/energy? text command and respond no when asked to Include diffusion at inlets?

Inlet diffusion cannot be turned off if you are using the density-based solver.     Previous: 5.2 Modeling Conductive and
Up: 5.2 Modeling Conductive and
Next: 5.2.2 Natural Convection and
Release 12.0 © ANSYS, Inc. 2009-01-23